I am just stumbling across this post now, but I can post a reply and hope this helps.
Inertia Relief is a way of constraining a component when there is no real feasible way of constraining or fixing it in space. The example given above of using it to fix components on which loads have been imported from Creo Mechanism is one applicable way. Another example is to think of an airplane. How do you specify "constraints" to simulate an airplane wing flying in the air? There is no true constraint that fully captures it, because every point on that air frame is deforming. Inertia relief constrains the model so that the solver can run it.
What does Inertia Relief do internally? It chooses a random area on the model, and creates a flexible 3-Point Constraint on the model that does not create any singularities, and does not force displacements in all directions to be zero (it fixes the out of plane translation, and by choosing 3 different points, the in-plane translations are constrained, but on different points, so that the constraint does not artificially stiffen the model i.e. if the In-Plane area is the XY plane, the X direction can be constrained on Point 1, and the Y direction free, while Point 2 can free the X direction and fix the Y direction. The result is a constrained model that is free to deform in plane if the model wants to.)
From the example of an airplane above, the 3 Point Constraint would be similar to choosing a passenger on the plane, specifying that passenger as the "zero/reference" point, and then measuring all displacement of the wings from the perspective of that passenger and how he sees it. Of course, how the wings displace then become relative to which passenger you choose as the reference point (displacement of the wings would look different to a passenger sitting in the front of the plane as compared to one sitting in the middle for example), BUT stresses and strains don't depend on the reference (in other words, the stresses and strains in the plane wings are the same regardless of whether you view it from the perspective of the front passenger, or the middle passenger).
Next time you run an Inertia Relief model, you will always notice that there is one spot that has zero displacements, and yet there is no stress singularity at that area, while the rest of the model deforms in relation to that. And the Stresses and Strains will come out independent of the reference point that Simulate automatically chooses.
How to use it?
When you know where your model is fixed in relation to the surroundings (bolt locations, attachment points, symmetry planes, e.t.c.), you want to create regular constraints. When you come across a situation where there is no feasible way to constrain the model without artificially stiffening the model, and preventing movement in an area that would typically move, then you want to use Inertia Relief. And when you use it, and interpret the results, understand that the displacements are relative to a reference point, but the stresses and strains are accurate.
Hope this helps.