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Aug 2, 2023 9:50 AM UTC
Solved

Issue creating a wrap

I want to create a quilt and then wrap a sketch around said quilt. 

To do this, I create a circle with diameter 360/pi and then extrude the sketch to 250. I create a sketch of a rectangle with height matching the extrusion and width 72. If I set the width to be 80 the wrap is successful but if I put the width to be 72 it fails. I have no idea why and would appreciate all help.

 

I am using Creo parametric 9.0 Student version.

kdirthAnswer
Aug 2, 2023 12:49 PM UTC

I would guess the issue is related to part of your sketch being on the very edge of the surface you are projecting onto.  As @MartinHanak indicated the entire sketch must lie within the surface.  The model has a level of accuracy that can cause an issue when you are defining the sketch to extend to the edge of the surface.  the copy of surfaces may also be contributing to the error.

 

On another note, I know you are a student, but this is a two feature curve created with 9 features.  Extrude the cylinder as a surface with an internal sketch and wrap an internal sketch from the front datum plane.  No need to copy surfaces and remove solids.

kdirth_0-1690980479710.png

Creo 7 file attached.

14 replies

Aug 2, 2023 9:55 AM UTC

The sketch.

IbrahimTayyab_0-1690970029435.png

The wrap error.

IbrahimTayyab_1-1690970063464.png

Same wrap working when I set the width to be 80 instead.

IbrahimTayyab_2-1690970128854.png

 

 

 

kdirthAnswer
Aug 2, 2023 12:49 PM UTC

I would guess the issue is related to part of your sketch being on the very edge of the surface you are projecting onto.  As @MartinHanak indicated the entire sketch must lie within the surface.  The model has a level of accuracy that can cause an issue when you are defining the sketch to extend to the edge of the surface.  the copy of surfaces may also be contributing to the error.

 

On another note, I know you are a student, but this is a two feature curve created with 9 features.  Extrude the cylinder as a surface with an internal sketch and wrap an internal sketch from the front datum plane.  No need to copy surfaces and remove solids.

kdirth_0-1690980479710.png

Creo 7 file attached.

Aug 2, 2023 2:46 PM UTC

Oh i never realised there was an option to extrude as a surface, that is so helpful. I just  burst out laughing when I realised this, thank you very much.

Aug 2, 2023 10:01 AM UTC

When I started the process in a new part it behaved as expected. I am not sure what caused this behaviour, I will try to recreate it in a new part.

Aug 2, 2023 11:56 AM UTC

@IbrahimTayyab wrote:

I have recorded a video of me creating the wrap in real time. I used the following relations:

Perimeter=360
radius=perimeter/2/pi
diameter=2*radius
extrude=300
width=72

Kindly let me know what I am doing wrong.

 


Hi,

wrapped curve must lie inside surface.

Aug 2, 2023 12:21 PM UTC

I am not sure I follow in the first sketch the height was constrained by the end references while in the second sketch the wrap failed when the sketch height was 300 same as the extrude

Aug 2, 2023 12:24 PM UTC

@IbrahimTayyab wrote:

I am not sure I follow in the first sketch the height was constrained by the end references while in the second sketch the wrap failed when the sketch height was 300 same as the extrude


Hi,

I apologize ... unfortunately I can't test all your attempts. I give up.

Aug 2, 2023 12:38 PM UTC

This may be an accuracy issue. Go to file prepare model properties, then change the accuracy to the smallest number it will let you.

You should be set to absolute accuracy also.

Aug 2, 2023 1:10 PM UTC

No matter my construction method of the geometry, I could not make it fail like it did on your geometry, unless I went over 300 on the height, which makes sense.

Aug 2, 2023 1:47 PM UTC

I was able to get a failure only when using copied surfaces and some widths worked and some didn't.  If I extruded a cylindrical surface and wrapped it, it worked for all widths.

Creo 7.0.11.0, absolute 0.001,  mmKs

Aug 2, 2023 2:48 PM UTC

Thanks for all your help, I think it will be resolved when I implement kidrth and stephenw's solution of extruding as a surface and checking the accuracy.